UK - 01926 333777
ROI - 01 297 4440
01926 333777
SOLIDWORKS Elite Specialists

Geometry Pattern

Tuesday September 1, 2015 at 11:46am
Building patterns of features is an easy task in SOLIDWORKS. However, having numerous instances of complex geometry may put too much strain on your machine and significantly reduce rebuild times. Geometry Pattern option is a nice trick to reduce the computational complexity of your patterns.  

Let’s start off with making a simple box. Make a rectangular sketch on Front Plane and extrude it to 50 mm.

Create another rectangular sketch on the top face of the box. Use it to perform an Extruded Cut offset by 5 mm from the bottom face of the box.  


Finish off with a Linear Pattern of the Extruded Cut. Make 8 instances of the feature along the length of the box. Set spacing at 10 mm.  


Easy enough. Now let’s run diagnostics on this part to check the rebuild times. Select Tools->Feature Statistics. A window will pop up listing the rebuild times for each feature. At this point Linear Pattern is taking 61% of the time to rebuild the model.  


We can reduce this in just a few mouse clicks by simply editing the Linear Pattern feature and ticking the box where it says “Geometry Pattern” under the “Options” tab.


Accept changes and run Feature Statistics once again.


Nothing has changed geometrically yet rebuild time is now reduced by 20 milliseconds. Although not a massive improvement in this simple case, such a change would significantly cut the rebuild times for complex geometry.

So what’s the catch? – Geometry pattern reduces calculations by simply copying the geometry of the seed part. Having that option disabled would pass on all of the seed feature references and relations to pattern instances.

The part below was made exactly the same way as the first one except the bottom face is now curved. Note how surface offset relation is retained for the pattern instances in the first case. This is all lost when Geometry Pattern is enabled.  


Second case is faster to rebuild however does not meet the design intent.


Related Blog Posts

Creating Interactive Animations with SOLIDWORKS
Interactive Images are a great export option within Visualize Professional, allowing you to view the model in a series of 360 orbital spins within a web browser. However, what happens if I want to use this interactive method to demonstrate a mechanis...
Working with Imported Geometry Webcast Series
SOLIDWORKS is able to import and edit a large number of different CAD file formats, this webcast series aims to explain what you need to know to make this process as smooth and efficient as possible.
SOLIDWORKS Dimensions - Collated Quick Tips
We have collated some of our favourite tips on creating, manipulating and controlling dimensions in SOLIDWORKS, both at a sketching and drawing level. Read on to find out moreā€¦